-
Notifications
You must be signed in to change notification settings - Fork 1
/
usermat3d.F
400 lines (395 loc) · 16 KB
/
usermat3d.F
1
2
3
4
5
6
7
8
9
10
11
12
13
14
15
16
17
18
19
20
21
22
23
24
25
26
27
28
29
30
31
32
33
34
35
36
37
38
39
40
41
42
43
44
45
46
47
48
49
50
51
52
53
54
55
56
57
58
59
60
61
62
63
64
65
66
67
68
69
70
71
72
73
74
75
76
77
78
79
80
81
82
83
84
85
86
87
88
89
90
91
92
93
94
95
96
97
98
99
100
101
102
103
104
105
106
107
108
109
110
111
112
113
114
115
116
117
118
119
120
121
122
123
124
125
126
127
128
129
130
131
132
133
134
135
136
137
138
139
140
141
142
143
144
145
146
147
148
149
150
151
152
153
154
155
156
157
158
159
160
161
162
163
164
165
166
167
168
169
170
171
172
173
174
175
176
177
178
179
180
181
182
183
184
185
186
187
188
189
190
191
192
193
194
195
196
197
198
199
200
201
202
203
204
205
206
207
208
209
210
211
212
213
214
215
216
217
218
219
220
221
222
223
224
225
226
227
228
229
230
231
232
233
234
235
236
237
238
239
240
241
242
243
244
245
246
247
248
249
250
251
252
253
254
255
256
257
258
259
260
261
262
263
264
265
266
267
268
269
270
271
272
273
274
275
276
277
278
279
280
281
282
283
284
285
286
287
288
289
290
291
292
293
294
295
296
297
298
299
300
301
302
303
304
305
306
307
308
309
310
311
312
313
314
315
316
317
318
319
320
321
322
323
324
325
326
327
328
329
330
331
332
333
334
335
336
337
338
339
340
341
342
343
344
345
346
347
348
349
350
351
352
353
354
355
356
357
358
359
360
361
362
363
364
365
366
367
368
369
370
371
372
373
374
375
376
377
378
379
380
381
382
383
384
385
386
387
388
389
390
391
392
393
394
395
396
397
398
399
400
*deck,usermat3d USERDISTRIB parallel gal
subroutine usermat3d(
& matId, elemId,kDomIntPt, kLayer, kSectPt,
& ldstep,isubst,keycut,
& nDirect,nShear,ncomp,nStatev,nProp,
& Time,dTime,Temp,dTemp,
& stress,ustatev,dsdePl,sedEl,sedPl,epseq,
& Strain,dStrain, epsPl, prop, coords,
& var0, defGrad_t, defGrad,
& tsstif, epsZZ, cutFactor,
& var1, var2, var3, var4, var5,
& var6, var7)
c*************************************************************************
c *** primary function ***
c
c user defined material constitutive model
c
c Attention:
c User must define material constitutive law properly
c according to the stress state such as 3D, plane strain
c and axisymmetry, plane stress and beam.
c
c a 3D material constitutive model can use for
c plane strain and axisymmetry cases.
c
c When using shell elements, a plane stress algorithm
c must be use.
c
c gal July, 1999
c
c The following demonstrates a USERMAT subroutine for
c a plasticity model of 3D solid elements or plane elements
c in plane strain or axisymmetric stress state. The plasticity
c model is the same as TB, BISO.
c See "ANSYS user material subroutine USERMAT" for detailed
c description of how to write a USERMAT routine.
c
c*************************************************************************
c
c input arguments
c ===============
c matId (int,sc,i) material #
c elemId (int,sc,i) element #
c kDomIntPt (int,sc,i) "k"th domain integration point
c kLayer (int,sc,i) "k"th layer
c kSectPt (int,sc,i) "k"th Section point
c ldstep (int,sc,i) load step number
c isubst (int,sc,i) substep number
c nDirect (int,sc,in) # of direct components
c nShear (int,sc,in) # of shear components
c ncomp (int,sc,in) nDirect + nShear
c nstatev (int,sc,l) Number of state variables
c nProp (int,sc,l) Number of material ocnstants
c
c Temp (dp,sc,in) temperature at beginning of
c time increment
c dTemp (dp,sc,in) temperature increment
c Time (dp,sc,in) time at beginning of increment (t)
c dTime (dp,sc,in) current time increment (dt)
c
c Strain (dp,ar(ncomp),i) Strain at beginning of time increment
c dStrain (dp,ar(ncomp),i) Strain increment
c prop (dp,ar(nprop),i) Material constants defined by TB,USER
c coords (dp,ar(3),i) current coordinates
c defGrad_t(dp,ar(3,3),i) Deformation gradient at time t
c defGrad (dp,ar(3,3),i) Deformation gradient at time t+dt
c
c input output arguments
c ======================
c stress (dp,ar(nTesn),io) stress
c ustatev (dp,ar(nstatev),io) user state variable
c ustatev(1) - equivalent plastic strain
c ustatev(2) - statev(1+ncomp) - plastic strain vector
c ustatev(nStatev) - von-Mises stress
c sedEl (dp,sc,io) elastic work
c sedPl (dp,sc,io) plastic work
c epseq (dp,sc,io) equivalent plastic strain
c tsstif (dp,ar(2),io) transverse shear stiffness
c tsstif(1) - Gxz
c tsstif(2) - Gyz
c tsstif(1) is also used to calculate hourglass
c stiffness, this value must be defined when low
c order element, such as 181, 182, 185 with uniform
c integration is used.
c var? (dp,sc,io) not used, they are reserved arguments
c for further development
c
c output arguments
c ================
c keycut (int,sc,io) loading bisect/cut control
c 0 - no bisect/cut
c 1 - bisect/cut
c (factor will be determined by ANSYS solution control)
c dsdePl (dp,ar(ncomp,ncomp),io) material jacobian matrix
c epsZZ (dp,sc,o) strain epsZZ for plane stress,
c define it when accounting for thickness change
c in shell and plane stress states
c cutFactor(dp,sc,o) time step size cut-back factor
c define it if a smaller step size is wished
c recommended value is 0~1
c
c*************************************************************************
c
c ncomp 6 for 3D (nshear=3)
c ncomp 4 for plane strain or axisymmetric (nShear = 1)
c ncomp 3 for plane stress (nShear = 1)
c ncomp 3 for 3d beam (nShear = 2)
c ncomp 1 for 1D (nShear = 0)
c
c stresss and strains, plastic strain vectors
c 11, 22, 33, 12, 23, 13 for 3D
c 11, 22, 33, 12 for plane strain or axisymmetry
c 11, 22, 12 for plane stress
c 11, 13, 12 for 3d beam
c 11 for 1D
c
c material jacobian matrix
c 3D
c dsdePl | 1111 1122 1133 1112 1123 1113 |
c dsdePl | 2211 2222 2233 2212 2223 2213 |
c dsdePl | 3311 3322 3333 3312 3323 3313 |
c dsdePl | 1211 1222 1233 1212 1223 1213 |
c dsdePl | 2311 2322 2333 2312 2323 2313 |
c dsdePl | 1311 1322 1333 1312 1323 1313 |
c plane strain or axisymmetric (11, 22, 33, 12)
c dsdePl | 1111 1122 1133 1112 |
c dsdePl | 2211 2222 2233 2212 |
c dsdePl | 3311 3322 3333 3312 |
c dsdePl | 1211 1222 1233 1212 |
c plane stress (11, 22, 12)
c dsdePl | 1111 1122 1112 |
c dsdePl | 2211 2222 2212 |
c dsdePl | 1211 1222 1212 |
c 3d beam (11, 13, 12)
c dsdePl | 1111 1113 1112 |
c dsdePl | 1311 1313 1312 |
c dsdePl | 1211 1213 1212 |
c 1d
c dsdePl | 1111 |
c
c*************************************************************************
#include "impcom.inc"
c
INTEGER
& matId, elemId,
& kDomIntPt, kLayer, kSectPt,
& ldstep,isubst,keycut,
& nDirect,nShear,ncomp,nStatev,nProp
DOUBLE PRECISION
& Time, dTime, Temp, dTemp,
& sedEl, sedPl, epseq, epsZZ, cutFactor
DOUBLE PRECISION
& stress (ncomp ), ustatev (nStatev),
& dsdePl (ncomp,ncomp),
& Strain (ncomp ), dStrain (ncomp ),
& epsPl (ncomp ), prop (nProp ),
& coords (3),
& defGrad (3,3), defGrad_t(3,3),
& tsstif (2)
c
c***************** User defined part *************************************
c
c --- parameters
c
INTEGER mcomp
DOUBLE PRECISION HALF, THIRD, ONE, TWO, SMALL, ONEHALF,
& ZERO, TWOTHIRD, ONEDM02, ONEDM05, sqTiny
PARAMETER (ZERO = 0.d0,
& HALF = 0.5d0,
& THIRD = 1.d0/3.d0,
& ONE = 1.d0,
& TWO = 2.d0,
& SMALL = 1.d-08,
& sqTiny = 1.d-20,
& ONEDM02 = 1.d-02,
& ONEDM05 = 1.d-05,
& ONEHALF = 1.5d0,
& TWOTHIRD = 2.0d0/3.0d0,
& mcomp = 6
& )
c
c --- local variables
c
c sigElp (dp,ar(6 ),l) trial stress
c dsdeEl (dp,ar(6,6),l) elastic moduli
c sigDev (dp,ar(6 ),l) deviatoric stress tensor
c dfds (dp,ar(6 ),l) derivative of the yield function
c JM (dp,ar(6,6),l) 2D matrix for a 4 order tensor
c pEl (dp,sc ,l) hydrostatic pressure stress
c qEl (dp,sc ,l) von-mises stress
c pleq_t (dp,sc ,l) equivalent plastic strain at beginnig of time increment
c pleq (dp,sc ,l) equivalent plastic strain at end of time increment
c dpleq (dp,sc ,l) incremental equivalent plastic strain
c sigy_t (dp,sc ,l) yield stress at beginnig of time increments
c sigy (dp,sc ,l) yield stress at end of time increment
c young (dp,sc ,l) Young's modulus
c posn (dp,sc ,l) Poiss's ratio
c sigy0 (dp,sc ,l) initial yield stress
c dsigdep (dp,sc ,l) plastic slop
c twoG (dp,sc ,l) two time of shear moduli
c threeG (dp,sc ,l) three time of shear moduli
c
c --- temperary variables for solution purpose
c i, j
c threeOv2qEl, oneOv3G, qElOv3G, con1, con2, fratio
c
EXTERNAL vzero, vmove, get_ElmData
DOUBLE PRECISION sigElp(mcomp), dsdeEl(mcomp,mcomp), G(mcomp),
& sigDev(mcomp), JM (mcomp,mcomp), dfds(mcomp),
& sigi (mcomp), strainEl(mcomp)
DOUBLE PRECISION var0, var1, var2, var3, var4, var5,
& var6, var7
DATA G/1.0D0,1.0D0,1.0D0,0.0D0,0.0D0,0.0D0/
c
INTEGER i, j
DOUBLE PRECISION pEl, qEl, pleq_t, sigy_t , sigy,
& dpleq, pleq,
& young, posn, sigy0, dsigdep,
& elast1,elast2,
& twoG, threeG, oneOv3G, qElOv3G, threeOv2qEl,
& fratio, con1, con2, dperr(3)
c*************************************************************************
c
keycut = 0
cutFactor = 0.d0
dsigdep = ZERO
pleq_t = ustatev(1)
pleq = pleq_t
c *** get Young's modulus and Poisson's ratio, initial yield stress and others
young = prop(1)
posn = prop(2)
sigy0 = prop(3)
c *** plastic strain tensor
call vmove(ustatev(2), epsPl(1), ncomp)
c *** calculate plastic slope
dsigdep = young*prop(4)/(young-prop(4))
twoG = young / (ONE+posn)
threeG = ONEHALF * twoG
elast1=young*posn/((1.0D0+posn)*(1.0D0-TWO*posn))
elast2=HALF*twoG
c *** define tsstif(1) since it is used for calculation of hourglass stiffness
tsstif(1) = elast2
c
c *** calculate elastic stiffness matrix (3d)
c
dsdeEl(1,1)=(elast1+TWO*elast2)*G(1)*G(1)
dsdeEl(1,2)=elast1*G(1)*G(2)+elast2*TWO*G(4)*G(4)
dsdeEl(1,3)=elast1*G(1)*G(3)+elast2*TWO*G(5)*G(5)
dsdeEl(1,4)=elast1*G(1)*G(4)+elast2*TWO*G(1)*G(4)
dsdeEl(1,5)=elast1*G(1)*G(5)+elast2*TWO*G(1)*G(5)
dsdeEl(1,6)=elast1*G(1)*G(6)+elast2*TWO*G(4)*G(5)
dsdeEl(2,2)=(elast1+TWO*elast2)*G(2)*G(2)
dsdeEl(2,3)=elast1*G(2)*G(3)+elast2*TWO*G(6)*G(6)
dsdeEl(2,4)=elast1*G(2)*G(4)+elast2*TWO*G(1)*G(4)
dsdeEl(2,5)=elast1*G(2)*G(5)+elast2*TWO*G(1)*G(5)
dsdeEl(2,6)=elast1*G(2)*G(6)+elast2*TWO*G(2)*G(6)
dsdeEl(3,3)=(elast1+TWO*elast2)*G(3)*G(3)
dsdeEl(3,4)=elast1*G(3)*G(4)+elast2*TWO*G(5)*G(6)
dsdeEl(3,5)=elast1*G(3)*G(5)+elast2*TWO*G(5)*G(3)
dsdeEl(3,6)=elast1*G(3)*G(6)+elast2*TWO*G(6)*G(3)
dsdeEl(4,4)=elast1*G(4)*G(4)+elast2*(G(1)*G(2)+G(4)*G(4))
dsdeEl(4,5)=elast1*G(4)*G(5)+elast2*(G(1)*G(6)+G(5)*G(4))
dsdeEl(4,6)=elast1*G(4)*G(6)+elast2*(G(4)*G(6)+G(5)*G(2))
dsdeEl(5,5)=elast1*G(5)*G(5)+elast2*(G(1)*G(3)+G(5)*G(5))
dsdeEl(5,6)=elast1*G(5)*G(6)+elast2*(G(4)*G(3)+G(5)*G(6))
dsdeEl(6,6)=elast1*G(6)*G(6)+elast2*(G(2)*G(3)+G(6)*G(6))
do i=1,ncomp-1
do j=i+1,ncomp
dsdeEl(j,i)=dsdeEl(i,j)
end do
end do
c
c
c *** get initial stress
call vzero(sigi(1),ncomp)
i = ncomp
call get_ElmData ('ISIG', elemId,kDomIntPt, i, sigi)
c
c *** calculate the trial stress and
c copy elastic moduli dsdeEl to material Jacobian matrix
do i=1,ncomp
strainEl(i) = Strain(i) + dStrain(i) - epsPl(i)
end do
call vzero(sigElp, 6)
do i=1,ncomp
do j=1,ncomp
dsdePl(j,i) = dsdeEl(j,i)
sigElp(i) = sigElp(i)+dsdeEl(j,i)*strainEl(j)
end do
sigElp(i) = sigElp(i) + sigi(i)
end do
c *** hydrostatic pressure stress
pEl = -THIRD * (sigElp(1) + sigElp(2) + sigElp(3))
c *** compute the deviatoric stress tensor
sigDev(1) = sigElp(1) + pEl
sigDev(2) = sigElp(2) + pEl
sigDev(3) = sigElp(3) + pEl
sigDev(4) = sigElp(4)
sigDev(5) = sigElp(5)
sigDev(6) = sigElp(6)
c *** compute von-mises stress
qEl =
& sigDev(1) * sigDev(1)+sigDev(2) * sigDev(2)+
& sigDev(3) * sigDev(3)+
& TWO*(sigDev(4) * sigDev(4)+ sigDev(5) * sigDev(5)+
& sigDev(6) * sigDev(6))
qEl = sqrt( ONEHALF * qEl)
c *** compute current yield stress
sigy = sigy0 + dsigdep * pleq
c
fratio = qEl / sigy - ONE
c *** check for yielding
IF (sigy .LE. ZERO.or.fratio .LE. -SMALL) GO TO 500
c
sigy_t = sigy
threeOv2qEl = ONEHALF / qEl
c *** compute derivative of the yield function
DO i=1, ncomp
dfds(i) = threeOv2qEl * sigDev(i)
END DO
oneOv3G = ONE / (threeG + dsigdep)
qElOv3G = qEl * oneOv3G
c *** initial guess of incremental equivalent plastic strain
dpleq = qElOv3G - sigy * oneOv3G
pleq = pleq_t + dpleq
sigy = sigy0 + dsigdep * pleq
c
c *** update stresses
DO i = 1 , ncomp
stress(i) = sigElp(i) - TWOTHIRD * (qEl-sigy) * dfds(i)
END DO
c
c *** update plastic strains
DO i = 1 , nDirect
epsPl(i) = epsPl(i) + dfds(i) * dpleq
END DO
DO i = nDirect + 1 , ncomp
epsPl(i) = epsPl(i) + TWO * dfds(i) * dpleq
END DO
epseq = pleq
c *** Update state variables
ustatev(1) = pleq
do i=1,ncomp
ustatev(i+1) = epsPl(i)
end do
c *** Update plastic work
sedPl = sedPl + HALF * (sigy_t+sigy)*dpleq
c
c *** Material Jcobian matrix
c
IF (qEl.LT.sqTiny) THEN
con1 = ZERO
ELSE
con1 = threeG * dpleq / qEl
END IF
con2 = threeG/(threeG+dsigdep) - con1
con2 = TWOTHIRD * con2
DO i=1,ncomp
DO j=1,ncomp
JM(j,i) = ZERO
END DO
END DO
DO i=1,nDirect
DO j=1,nDirect
JM(i,j) = -THIRD
END DO
JM(i,i) = JM(i,i) + ONE
END DO
DO i=nDirect + 1,ncomp
JM(i,i) = HALF
END DO
DO i=1,ncomp
DO j=1,ncomp
dsdePl(i,j) = dsdeEl(i,j) - twoG
& * ( con2 * dfds(i) * dfds(j) + con1 * JM(i,j) )
END DO
END DO
c
goto 600
500 continue
c *** Update stress in case of elastic/unloading
do i=1,ncomp
stress(i) = sigElp(i)
end do
600 continue
sedEl = ZERO
DO i = 1 , ncomp
sedEl = sedEl + stress(i)*(Strain(i)+dStrain(i)-epsPl(i))
END DO
sedEl = sedEl * HALF
ustatev(nStatev) = sigy
c
! cutFactor = 0.5d0
return
end